Open your file — or describe the part you need
Drag in a STEP, STL, IGES, OBJ, DXF, BREP, or GLB file to view it in 3D — free, no signup to look. No file yet? Describe your part in Studio →
How to Read a Thread Callout on a Drawing: Metric, Inch and Pipe Threads
A thread callout is the note on a drawing that defines a screw thread: its size, its pitch or threads per inch, its tolerance class, and how deep it goes. This guide reads metric, inch and pipe callouts part by part, with the tap drill and depth lines that go with a tapped hole.
What is a thread callout?
A thread callout is a short note on a leader that points at a threaded hole or shaft. It names the thread form, the major diameter, the pitch, the tolerance class and the length or depth. Drawings show threads only in simplified form, so the callout carries everything the machinist needs to cut the thread.
A tapped hole usually gets two lines. The first is the tap drill: its diameter and its depth. The second is the thread: size, pitch, class and full-thread depth. A through hole replaces the depths with THRU. On many inch drawings the tap drill line is left off and the shop picks the drill from a chart.
- Thread form. M for ISO metric, UNC, UNF or UNEF for Unified inch threads, NPT or G for pipe threads, and a few others such as ACME for power screws.
- Size. The major diameter: the outside of a screw, or the largest diameter cut into a tapped hole.
- Pitch. The distance from one thread to the next in millimetres on metric threads, or threads per inch on inch threads.
- Class. The tolerance, and whether the thread is internal or external.
- Depth or length. How far the full thread runs, after the depth symbol ↧, or THRU.
How do you read a metric thread callout?
A metric callout reads M, the major diameter in millimetres, × the pitch in millimetres, then the tolerance class. M8×1.25 - 6H is an 8 mm internal thread with a 1.25 mm pitch. When the pitch is left off, the coarse pitch for that size is meant.
| Callout | What it means |
|---|---|
| M6 | M6 coarse (1 mm pitch), class not stated: usually 6H for a hole, 6g for a screw |
| M8×1.25 - 6H | 8 mm major diameter, 1.25 mm pitch (coarse), internal thread, medium class |
| M10×1 - 6g | 10 mm, 1 mm fine pitch, external thread, medium class |
| M12×1.75 - 6H ↧ 18 | 12 mm coarse, internal, full thread 18 mm deep |
| M16×1.5 - LH - 6g | 16 mm fine pitch, left-hand, external |
- Coarse is the default. M6 means 1 mm pitch, M8 1.25, M10 1.5, M12 1.75. A fine pitch, such as M10×1.25 or M10×1, is always written out.
- Capital or small letter. A capital (6H) is an internal thread, a small letter (6g) an external one. The number is the tolerance grade; 6 is the medium grade used on most parts.
- Two classes. A class such as 5g6g gives the pitch diameter and the major diameter separately. When both are the same, it is written once, as 6g.
- LH. Left-hand thread. With no LH, the thread is right-hand.
For the hole to drill and the clearance hole for each size, see the metric clearance hole size chart and the size pages such as M8 screw hole size.
How do you read an inch (Unified) thread callout?
An inch callout reads the size, a dash, the threads per inch, the series and the class. 1/4-20 UNC-2B is a quarter-inch internal thread with 20 threads per inch in the coarse series. Sizes under a quarter inch use numbers, such as #10-32.
| Callout | What it means |
|---|---|
| 1/4-20 UNC-2B | Quarter inch, 20 threads per inch, coarse series, internal, standard class |
| 1/4-28 UNF-2A | Quarter inch, 28 threads per inch, fine series, external, standard class |
| #10-32 UNF-2B | Number 10 (0.190 in), 32 threads per inch, fine series, internal |
| 3/8-16 UNC-3A | 3/8 inch coarse, external, tight class 3 |
| 1/2-13 UNC-2B ↧ .75 | Half inch coarse, internal, full thread 0.75 in deep |
- Series. UNC is coarse, UNF is fine, UNEF is extra fine. UN with a pitch, such as 1-12 UN, is a constant-pitch thread, and UNS is a special combination.
- Class. A is external, B is internal. Class 2 is the general-purpose fit, 3 is tighter, and 1 is loose, for parts that must go together dirty or damaged.
- Number sizes. #4 is 0.112 in, #6 0.138, #8 0.164 and #10 0.190 across the major diameter.
- Close but not equal. 1/4-20 and M6×1 are nearly the same size and will not mix. Read each callout as written, especially on an old inch drawing with a few metric holes.
What do the depth and tap drill lines mean on a tapped hole?
On a blind tapped hole, the depth after ↧ in the thread line is the full-thread depth. The tap drill line above it gives the drill diameter and a deeper drill depth, so the tap has room at the bottom. Both depths run from the face where the hole starts, to the end of the full diameter, not the drill point.
- Tap drill size. For metric coarse threads it is roughly the size minus the pitch: 6.8 mm for M8×1.25, 8.5 mm for M10×1.5. For 1/4-20 it is a #7 drill, 0.201 in.
- Why deeper. A tap is tapered at its tip and cannot cut full threads to the bottom of a blind hole. The extra drill depth also gives the chips somewhere to go.
- The older form. Some drawings write the depth in words: “1/4-20 UNC-2B X .50 DEEP” means the same as the depth symbol.
- Countersink at the top. A note such as “⌵ Ø10 X 90°” under the callout asks for a small countersink so the first thread does not burr over.
- Thread length on a shaft. On an external thread the length is dimensioned along the shaft, and a groove or a runout may be shown where the thread stops.
The depth symbol and the countersink and counterbore marks are explained with the rest of the drafting symbols in the engineering drawing symbols chart, and countersink vs counterbore compares those two.
How are pipe threads called out?
A pipe thread callout gives the nominal pipe size, the threads per inch and the form, such as 1/4-18 NPT. Most pipe threads are tapered so they seal as they tighten. The pipe size is not the thread diameter: a 1/4 NPT thread is a little over half an inch across.
| Callout | Thread | How it seals |
|---|---|---|
| 1/4-18 NPT | American taper pipe thread | Taper plus sealant or tape |
| 1/4-18 NPTF | American dryseal taper | Thread crests and roots seal with no sealant |
| 1/4-18 NPS | American straight pipe thread | Gasket or O-ring; the thread does not seal |
| R 1/4, Rc 1/4 | British taper, external (R) and internal (Rc) | Taper plus sealant |
| G 1/4 | British parallel | Washer or O-ring against a face |
- Taper. NPT and the British R threads taper 1 in 16 on the diameter. The depth on a tapped NPT hole is often given as a gauge reading or as a number of turns of hand engagement, not just a length.
- American and British do not mix. 1/4 NPT has 18 threads per inch and a 60° thread angle; 1/4 BSP has 19 and 55°. They may start together but will not seal.
- Hydraulic ports. Straight threads that seal with an O-ring, such as SAE straight-thread ports, are called out by their own standard and often show a spot face around the hole.
How are threads drawn in the views?
Drawings do not draw the helix. A thread is shown in simplified form: thick lines for the outside of the thread and thin or dashed lines for its root, with a circle in the end view. The callout, not the picture, defines the thread.
- External thread. The thick outline is the major diameter; the thin lines inside it are the root.
- Internal thread. Reversed: the hole is drawn at the tap drill size with thin lines outside it at the major diameter. In a section view the hatching runs to the drill size.
- End of the full thread. A thick line across the thread marks where full threads stop.
- Old drawings. Hand-drawn sheets sometimes use the schematic form, short thick and thin lines alternating along the thread. It means the same thing.
If you are drawing the thread rather than reading it, see how to add threads to a part.
Which thread callout mistakes cause trouble?
The costly mistakes are a missing depth on a blind hole, a fine pitch written as if it were coarse, an internal class on an external thread, and a metric callout read as inch or the other way round. Each makes a part that looks right and will not take its screw.
- No depth on a blind hole. The shop has to guess, or ask. A thread depth with no drill depth is normal; a drill depth with no thread depth is not.
- Pitch dropped from a fine thread. M10 on its own means 1.5 mm. If the mating part is M10×1.25, the callout has to say so.
- A and B, or H and g, swapped. A tapped hole called out 2A or 6g is a drafting slip. Read it as internal and flag it.
- Thread deeper than the drill. It cannot be made. One of the two numbers is wrong.
- Revisions that changed the size. A hole moved from 1/4-20 to M6 on a later revision may still show the old tap drill. Check both lines agree.
Reading the rest of the sheet in order is covered in how to read engineering drawings, and the general tolerance note that covers untoleranced sizes is decoded by the ISO 2768 calculator.
Does a 3D model carry the thread callout?
Usually not in full. Most CAD models and STEP files show a tapped hole as a plain hole, at the tap drill or the major diameter, and the thread itself stays in the drawing’s callout. Keep the drawing with the model so the size, pitch, class and depth are not lost.
- Hole position and depth live in the model and can be measured from it.
- The thread spec lives in the callout. Software that reads a model for a quote often asks you to mark threaded holes by hand for this reason.
- A modelled helix is rare outside 3D printing and makes the file much heavier.
For which file to send a shop with the drawing, see the best file format for a machine shop.
Frequently asked questions
What is a thread callout?
A thread callout is the note on a drawing that defines a screw thread: its size, its pitch or threads per inch, its tolerance class, and how deep it goes. It sits on a leader pointing at the hole or the shaft, because the thread itself is drawn only in a simplified form.
What does M8×1.25-6H mean?
It is a metric thread 8 mm in major diameter with a 1.25 mm pitch, the standard coarse pitch for M8. 6H is the tolerance class: a capital letter means an internal thread, a tapped hole. If the pitch is left off, as in M8-6H, the coarse pitch is meant.
What does 1/4-20 UNC-2B mean?
It is an inch thread a quarter inch in major diameter with 20 threads per inch, in the Unified coarse series. 2B is the class of fit: the B means an internal thread and 2 is the general-purpose class. The matching screw is 1/4-20 UNC-2A.
What is the difference between 6H and 6g?
Both are metric tolerance classes of the same grade. A capital letter (6H) is for an internal thread, a small letter (6g) for an external one. 6H/6g is the normal medium fit for general bolts and tapped holes, and a drawing that gives no class usually means it.
How deep should a tapped hole be?
Deep enough for the screw to engage about one to one and a half times its diameter in steel, more in aluminum or plastic. The drawing gives the full-thread depth; the tap drill must go deeper than that, because the tap cannot cut full threads right to the bottom of a blind hole.
What does NPT mean on a drawing?
NPT is the American National Pipe Taper thread. A callout such as 1/4-18 NPT gives the nominal pipe size and the threads per inch. The thread is tapered so it seals as it tightens, and the 1/4 is a pipe size, not the diameter of the thread.
Have a drawing full of tapped holes and need a 3D model?
Upload the drawing to Drawing to STEP from PartWork.ai. You get a STEP and an STL in minutes, from $29.99, with every hole at its position and depth, checked against every view of the drawing. Keep the drawing with the files for the thread callouts.
- Any print. A PDF, PNG or JPG, from CAD, a scanner or a phone photo, including old hand-drawn sheets.
- Questions, not guesses. When a dimension is faded, missing or conflicting, we ask you before the model is finished.
- Assemblies too. Weldments and assembly drawings are in scope when the parts are dimensioned.
It does not do freeform shapes yet. For the other routes to a model, see how to convert a PDF to CAD and CAD drafting services.
Export-controlled drawings (ITAR/EAR) aren’t accepted.